Live Tooling Lathe Programming
This is a live tooling lathe programming example which shows the use of driven tool (live tooling) and spindle orientation on Haas cnc lathe machine.
For a brief introduction of live tooling and related M-Codes on Haas cnc lathe machine read
- CNC Lathe Live Tooling Definition and Related Haas CNC M-Codes
- M19 Spindle Orientation – M119 Sub Spindle Orientation
- Haas CNC Lathe M-Codes
- Haas CNC Lathe G-Codes
Live Tooling Program Example Code
For same cnc program example which uses C-axis for spindle control read C-Axis Lathe Programming Example with Live Tooling on Haas CNC
CNC Spindle Orientation M19 Haas CNC Program Example
O0050 N10 T101 N15 G54 N20 G00 X3.0 Z0.1 N25 G98 N30 M19 P0 N35 M14 N40 M133 P2000 N45 G01 Z-0.5 F40.0 N50 G00 Z0.1 N55 M19 P120 N60 M14 N65 G01 Z-0.5 N70 G00 Z0.1 N75 M19 P240 N80 M14 N85 G01 Z-0.5 N90 G00 Z0.1 N95 M15
CNC Program Code Explanation
N25 G98 Feed per minute.
G98 Feed per minute is used in this program instead of G99 feed per spindle revolution, because with most live tooling code G98 (feed per minute) is used as the spindle is not rotating at high rpm.
N30 M19 P0 Orient spindle.
The Spindle Orientation option M19 allows spindle positioning to a specific programmed angle, for more info read M19 Spindle Orientation – M119 Sub Spindle Orientation.
N35 M14 Clamp Main Spindle or turns on the spindle brake.
N40 M133 P2000 Turn on live tool forward 2000 rpm.
N95 M15 Turn off main spindle brake.
